Peck drilling is one of those techniques that gets used either too much or not enough. Some machinists peck everything out of habit. Others avoid it because it slows the cycle. Neither approach is wrong in the right context, but neither is a strategy. Here's a decision framework that actually works.
Peck drilling — retracting the drill periodically to clear chips and allow coolant to flush the hole — solves two problems: chip evacuation and heat buildup. Both get worse as hole depth increases relative to diameter (depth-to-diameter ratio, or L/D).
At shallow L/D ratios under 3:1, chips evacuate reasonably well and a single pass is usually fine. As L/D increases beyond 3:1, chip packing becomes a real risk. Beyond 5:1, peck drilling is worth considering for most materials. Beyond 8:1, it's essentially required in everything except the most ideal conditions.
The specific L/D thresholds depend on material, flute geometry, coolant delivery, and spindle speed. Aluminum with through-spindle coolant can often be drilled deeper in a single pass than steel with flood coolant. The numbers above are starting points, not hard rules.
The most common peck cycle is the G83 canned cycle in CNC work — full retract to clear chips. The peck depth (Q value in G83) is the key variable. A useful starting point: peck depth equal to the drill diameter. A 1/2" drill pecks at 1/2" increments. In free-machining steels or aluminum, you can often go to 1.5–2x diameter per peck. In stainless, titanium, or work-hardening alloys, you may need to drop to 0.5x diameter or less.
The full retract in G83 ensures chip clearing but adds cycle time. For materials that don't pack aggressively, a chip-break peck (partial retract, G73) reduces cycle time while still breaking the chip. G73 doesn't fully clear chips — it breaks them — so it's only appropriate where coolant can flush adequately.
Peck drilling on shallow holes in tough materials causes more problems than it prevents. Every time you retract and re-enter, the drill re-engages the workpiece. In hardened or work-hardening materials (stainless, Inconel, high-manganese steel), re-entry work-hardens the material at the bottom of the hole. If you retract too often, you're repeatedly drilling into a harder surface. This accelerates edge wear and can cause premature chipping.
Through-spindle coolant is the tool that most often eliminates the need for peck drilling entirely. If coolant is delivered to the cutting zone at pressure, chips flush out continuously. Shops with through-spindle coolant typically reduce or eliminate peck cycles where flood-coolant shops would peck routinely.
A drill allowed to run too deep before retracting will pack chips against the workpiece wall, scoring the bore. Very short pecks in non-aggressive materials cause excessive re-entry and the associated edge wear. The practical approach: start with diameter-depth pecks, check chip condition on the first hole, and adjust. Chips that are long and stringy indicate the peck is too deep. Chips that are tiny, powdery, or discolored indicate too many re-entries and too much heat.
On a manual drill press, the feedback you're reading is quill resistance and sound. Pull back every time you feel resistance increase — retract the quill with the spindle still turning, clear the chips, then re-engage. The spindle shouldn't be stopped during retract. The key discipline is not waiting until the drill stalls or grabs to retract. By that point, chip packing is already compromising the hole. Retract at the first sign of increased resistance — you're retracting to prevent the condition, not respond to it.
SEND US YOUR DRILLS →